"""

name: tea_cup.py
by:   Gumyr
date: March 27th 2023

desc: This example demonstrates the creation a tea cup, which serves as an example of
      constructing complex, non-flat geometrical shapes programmatically.

      The tea cup model involves several CAD techniques, such as:
      - Revolve Operations: There is 1 occurrence of a revolve operation. This is used
        to create the main body of the tea cup by revolving a profile around an axis,
        a common technique for generating symmetrical objects like cups.
      - Sweep Operations: There are 2 occurrences of sweep operations. The handle are
        created by sweeping a profile along a path to generate non-planar surfaces.
      - Offset/Shell Operations: the bowl of the cup is hollowed out with the offset
        operation leaving the top open.
      - Fillet Operations: There is 1 occurrence of a fillet operation which is used to
        round the edges for aesthetic improvement and to mimic real-world objects more
        closely.

license:

    Copyright 2023 Gumyr

    Licensed under the Apache License, Version 2.0 (the "License");
    you may not use this file except in compliance with the License.
    You may obtain a copy of the License at

        http://www.apache.org/licenses/LICENSE-2.0

    Unless required by applicable law or agreed to in writing, software
    distributed under the License is distributed on an "AS IS" BASIS,
    WITHOUT WARRANTIES OR CONDITIONS OF ANY KIND, either express or implied.
    See the License for the specific language governing permissions and
    limitations under the License.
"""

# [Code]

from build123d import *
from ocp_vscode import show

wall_thickness = 3 * MM
fillet_radius = wall_thickness * 0.49

with BuildPart() as tea_cup:
    # Create the bowl of the cup as a revolved cross section
    with BuildSketch(Plane.XZ) as bowl_section:
        with BuildLine():
            # Start & end points with control tangents
            s = Spline(
                (30 * MM, 10 * MM),
                (69 * MM, 105 * MM),
                tangents=((1, 0.5), (0.7, 1)),
                tangent_scalars=(1.75, 1),
            )
            # Lines to finish creating ½ the bowl shape
            Polyline(s @ 0, s @ 0 + (10 * MM, -10 * MM), (0, 0), (0, (s @ 1).Y), s @ 1)
        make_face()  # Create a filled 2D shape
    revolve(axis=Axis.Z)
    # Hollow out the bowl with openings on the top and bottom
    offset(amount=-wall_thickness, openings=tea_cup.faces().filter_by(GeomType.PLANE))
    # Add a bottom to the bowl
    with Locations((0, 0, (s @ 0).Y)):
        Cylinder(radius=(s @ 0).X, height=wall_thickness)
    # Smooth out all the edges
    fillet(tea_cup.edges(), radius=fillet_radius)

    # Determine where the handle contacts the bowl
    handle_intersections = [
        tea_cup.part.find_intersection_points(
            Axis(origin=(0, 0, vertical_offset), direction=(1, 0, 0))
        )[-1][0]
        for vertical_offset in [35 * MM, 80 * MM]
    ]
    # Create a path for handle creation
    with BuildLine(Plane.XZ) as handle_path:
        Spline(
            handle_intersections[0] - (wall_thickness / 2, 0),
            handle_intersections[0] + (35 * MM, 30 * MM),
            handle_intersections[0] + (40 * MM, 60 * MM),
            handle_intersections[1] - (wall_thickness / 2, 0),
            tangents=((1, 1.25), (-0.2, -1)),
        )
    # Align the cross section to the beginning of the path
    with BuildSketch(handle_path.line ^ 0) as handle_cross_section:
        RectangleRounded(wall_thickness, 8 * MM, fillet_radius)
    sweep()  # Sweep handle cross section along path

assert abs(tea_cup.part.volume - 130326) < 1

show(tea_cup, names=["tea cup"])
# [End]
tea_cup.part.color = Color(0xDFDCDA)  # Porcelain
export_gltf(
    tea_cup.part,
    "tea_cup.glb",
    binary=True,
    linear_deflection=0.1,
    angular_deflection=1,
)